Wood Designer forum
DXF export to Vectric|Forum|WOOD DESIGNER
Home
October 4, 2012
Offline
Hi Gilmont,
It seems that the problem with the DXF output is coming from the superposition of the end of the bottom groove and side of the tongue and groove lines.
If the depth of the bottom groove is set to less that 8mm the end of groove lines do not then superpose the vertical tongue groove edge lines.
The resulting DXF has then 1 rectangle per groove.
I’d suggest that you set the groove depths in the same way. You can then extend the dxf groove lengths with extend options of the post processor.
I attach a drawer with the bottom groove set to 7mm deep as an example.
Hope this is helpful.
All the best,
Ness
Second try… Again, for some reason, the Web site won’t allow me to upload a ZIP file. I get a “File extension error.” message when trying. I changed the .zip extension to a .txt to “trick” the site. I assume that you can change it back to .zip to decompress. If there is an easier way to upload .zip files, please let me know.
Regards.
October 4, 2012
Offline
Hi Gilmond,
Your files don’t seem to have uploaded, can you put them in a zip and try again?
All the best,
Ness
Here they are…
The cabinet is a simple 1 drawer cabinet with nothing specific.
I’ve also included the Post processor configuration I used. Could you take a look at it and provide some advise on it… (note: I had to change the file extension from a .pr-reg extension to a .txt because the web site wouldn’t allow the upload.)
Thanks.
October 4, 2012
Offline
Hi Gilmont,
Can you post the Polyboard and DXF files?
All the best,
Ness
Thanks Ness, this is very helpful.
I have been able to resolve my issues with points 1,3 and 4 but I still have problems with the second one. For some reason, the grooves on the second face only show partially. It looks like the grooves on one face are “interrupted” when they cross a groove on the other face. I tried to illustrate it on the attach design. As you will see, the groove on face 2 is much shorter than expected, and groove on face 1 is splitted.
I can fix it in Aspire but it is not convenient and not practical when used at a large scale. Can you help?
Regards
Thanks Ness, this is very helpful.
I have been able to resolve my issues with points 1,3 and 4 but I still have problems with the second one. For some reason, the grooves on the second face only show partially. It looks like the grooves on one face are “interrupted” when they cross a groove on the other face. I tried to illustrate it on the attach design. As you will see, the groove on face 2 is much shorter than expected, and groove on face 1 is splitted.
I can fix it in Aspire but it is not convenient and not practical when used at a large scale. Can you help?
Regards
October 4, 2012
Offline
Hi Gilmont,
1-When cutting grooves with a saw, Polyboard DXF out put can be adjusted to compensate for the blade diameter.
When using DXF output for routing grooves with a milling bit set the blade diameter to “0” or “0.01” as the value doesn’t except “0”.
This has not side effects.
Note that in this case, it’s also useful to set “through groove over lap” to half the milling bit diameter and “Recess of non through grooves” to minus the radius of the milling bit.
2- You should set the “Tool faces export” to ‘one exported file per face” this creates a machine DXF file that you use per face.
3- You must add a “depth” variable to the layer names so that each specific groove depth creates a specific layer.
4- Same for the holes.
In général it’s very easy to set up templates for Vcarve with Polyboard and they work very well. Once set up all is automatic so it makes a very nice and efficent work flow.
We don’t have a user guide but we can help you set up your configuration if you buy a support pack:
Have a look on our 1-2-1 Training page here:
https://wooddesigner.org/train…..g-service/
All the best,
Ness
Hi,
I am fairly new and still in discovery mode of Polyboard. I am planning to use it to build some simple cabinets that I would then machine on a CNC.
While experimenting, I faced the following issues:
1. When exporting my DXF’s I noticed the “Blade Diameter” parameter had an influence on the Groove’s length that were exported. Can you provide some details on how to use that parameter? I set it to the smallest value I could, otherwise the Grooves got shortened but I am not sure this had a side effect I didn’t notice.
2. When exporting panels that are grooved on both sides, Polyboard only exports the outline of the Grooves on one face. How can I fix that? Ideally, I would like to have one DXF file with vectors for both faces in different color.
3. I tried to use the Toolpath templates to assign automatic toolpaths to the Groove vectors but Vectric wouldn’t assign the depth cut of the toolpath because all Grooves didn’t have the same depth. Is there a way to have different Groove depth assigned to different layers?
4. I have a similar issue as #3 with drilling holes that have different depth.
Sorry for the long list of questions. I tried to find answers on the forum but couldn’t find anything on export to Vectric or Post processors configuration. Is there a user guide or video tutorial you could forward me to?
Thanks for your help.
Gilles.
1 Guest(s)
